Skip to main content

Machining Tool Steels (D2, H13, S7): Challenges and Approaches

Tool steels present machining challenges qualitatively different from standard alloy steels. UTEC Industrial provides precision CNC machining services for large and oversized industrial components in the Pacific Northwest, with in-house heat treatment and induction hardening integrated into the machining workflow. D2 contains 11–13% chromium and vanadium carbides that abrade carbide tooling rapidly. H13 must often be machined at 44–52 HRC using CBN or ceramic tooling. S7 combines high toughness with work-hardening tendency. This article covers machining approaches for D2, H13, and S7 in annealed and hardened conditions — insert grades, cutting parameters, and operational practices that make tool steel machining productive.

What makes tool steels difficult to machine compared to standard alloy steels?​

Tool steels are difficult to machine for three interconnected reasons: high alloy carbide content, elevated hardness even in the annealed condition, and thermal sensitivity that penalizes incorrect cutting parameters more severely than with standard steels. High carbide content in D2 and other high-chromium tool steels: D2 contains 1.4–1.6% carbon and 11–13% chromium, producing a microstructure saturated with chromium carbide (Cr₇C₃ and Cr₂₃C₆) particles that are significantly harder than the carbide cutting tool substrate at elevated temperatures. The carbide particles in D2 reach 1,400–1,600 HV (approximately 80 HRC equivalent) — harder than the cobalt-matrix carbide tool, which softens above 600°C. The result is abrasion-dominated flank wear at a rate 3–5× faster than equivalent cuts on 4140 at the same parameters. Elevated annealed hardness: D2 in the fully annealed condition is 255 HB minimum — harder than normalized 4140 (241 HB) and approaching the range where carbide insert wear rate becomes significant. H13 in the service condition (44–52 HRC) cannot be machined by standard carbide at all — the tool tip softens before the workpiece yields, producing immediate catastrophic wear. Thermal sensitivity and work hardening: S7 and other shock-resisting tool steels work harden rapidly in the deformed surface layer, much like austenitic stainless — each pass creates a harder layer that the next pass must cut through, progressively increasing the specific cutting force and heat generation. If the cutting parameters are at the edge of the tool's capability with fresh-condition material, the work-hardened layer will push the tool beyond its capability, causing sudden edge failure rather than gradual wear (ASM Handbook, Vol. 16, ASM International, 1989; Roberts et al., Tool Steels, 5th ed., ASM International, 1998).

D2 in the annealed condition (255–269 HB, spheroidized microstructure) is the most common machining condition for rough profiling, boring, and turning of D2 components before hardening. The soft annealed condition minimizes the cutting temperature required to shear the material, but the high carbide content still produces above-average abrasive wear on tooling. Recommended parameters for CNC turning of annealed D2: cutting speed 150–250 SFM (significantly lower than the 350–500 SFM for annealed 4140 — the reduced speed keeps cutting temperature below the point where the chromium carbides abrade the insert at maximum rate). Feed 0.008–0.015 ipr; depth of cut 0.050–0.150 inch for roughing, 0.020–0.050 inch for semi-finishing. Insert grade: submicron-grain carbide (ISO M15–M25 or K10–K20 equivalent) with TiAlN or AlCrN PVD coating. The fine grain carbide substrate resists abrasive wear better than standard-grain grades. TiAlN coating adds oxidation resistance at the elevated temperatures generated by the chromium carbides. Chip breaker: M-geometry or a lightly positive geometry — avoid highly positive geometries because D2's interrupted carbide microstructure creates micro-impacts at the cutting edge that chip lightly positive edges. Coolant: flood semi-synthetic at 8–10% concentration with sulfurized EP additives. High flow rate is important for D2 — the carbide particles generate abrasive heat even at reduced cutting speeds, and removing that heat with aggressive coolant application extends insert life. Do not use ceramic inserts on annealed D2 — ceramics perform poorly on interrupted or carbide-rich cuts and are reserved for hardened-condition machining (Roberts et al., Tool Steels, 5th ed., ASM International, 1998; Machinery's Handbook, 31st ed., Industrial Press, 2020).

How is D2 machined after hardening and what tooling is required?​

D2 in the hardened condition (58–62 HRC for standard cold-work service) cannot be machined with conventional carbide tooling — the tool tip collapses within seconds of entering the cut. The productive machining of hardened D2 requires CBN (cubic boron nitride) or ceramic inserts, and the parameters must be carefully matched to the insert grade's thermal and mechanical requirements. CBN for hardened D2: solid CBN or CBN-tipped inserts (PCBN) in grades formulated for high-chromium steels — not all CBN grades perform well on D2. The chromium carbide content in D2 is abrasive to all cutting materials, including CBN, but at the speeds used for hard turning, the cutting temperature is high enough that the carbides in the workpiece soften relative to CBN's hot hardness, reversing the abrasive relationship that prevails at lower speeds. Cutting parameters for CBN turning of hardened D2: speed 100–200 SFM (lower than CBN parameters for 4340 at similar hardness — the chromium carbides limit CBN speed); feed 0.003–0.008 ipr; depth of cut 0.005–0.025 inch (very light, consistent with hard turning practice); no coolant or continuous air blast (CBN is thermal-shock sensitive — interrupted coolant causes edge cracking). Ceramic inserts (mixed alumina Al₂O₃/TiC): an alternative to CBN for lighter finishing passes on hardened D2; less expensive than PCBN but with lower toughness — ceramic is more brittle than CBN and is not suitable for interrupted cuts. For grinding after hard turning: D2 is routinely ground to final dimensions in the hardened state using vitrified aluminum oxide or CBN wheels. Profile grinding is the standard finishing method for complex D2 tool profiles that cannot be produced to final dimensions by hard turning alone (Roberts et al., Tool Steels, 5th ed., ASM International, 1998; Sandvik Coromant, Metalcutting Technical Guide).

What parameters and approach are used for machining H13 hot-work tool steel?​

H13 is a chromium-molybdenum-vanadium hot-work tool steel most commonly encountered in service at 44–52 HRC — the hardness range for die casting dies, extrusion tooling, and hot forging tools. Like D2, H13 in the annealed condition (192–229 HB) is machinable with carbide tooling at reduced parameters; in the hardened service condition, CBN or ceramic is required. Annealed H13 machining parameters: cutting speed 200–300 SFM; feed 0.008–0.015 ipr; depth of cut 0.050–0.200 inch roughing. Insert grade: PVD TiAlN-coated submicron carbide. H13 in the annealed condition is less abrasive than D2 (lower chromium content, 4.75–5.5% vs. 11–13%; lower carbon content, 0.32–0.45% vs. 1.40–1.60%) — carbide tooling performs significantly better on annealed H13 than on annealed D2. Hardened H13 at 44–48 HRC: CBN inserts, 150–300 SFM, 0.004–0.010 ipr, 0.010–0.030 inch depth. Continuous air blast preferred over flood coolant. At 44–48 HRC, H13 is machinable with CBN at moderate material removal rates — productive finish turning of hardened H13 at 0.010-inch depth produces useful dimensional correction that avoids post-hardening grinding for many simple shapes. At 50–52 HRC: CBN is still productive for finishing, but the tool life is shorter and the depth of cut limit drops to 0.005–0.015 inch. A common machining approach for H13 repair work — refurbishing worn die surfaces — uses CBN to remove the worn layer and bring the critical surfaces back to geometry, then returns to a secondary hardening treatment if the die has additional service life remaining. The key process discipline for hardened H13: never stop a CBN turning pass midway and restart in the same place — the dwell creates a stress concentration that may crack the CBN insert. Program full-pass cuts only; if a pass must be interrupted, retract the tool fully and restart from outside the workpiece (Roberts et al., Tool Steels, 5th ed., ASM International, 1998; Sandvik Coromant, Metalcutting Technical Guide).

How is S7 shock-resisting tool steel machined and what makes it different from D2 and H13?​

S7 shock-resisting tool steel (0.45–0.55% C, 3.00–3.50% Cr, 1.20–1.75% Mo, low vanadium) is designed for high toughness and resistance to impact loading — a combination that makes it mechanically different from D2 and H13 in ways that affect machining behavior. S7 in the annealed condition (187–229 HB) machines at parameters similar to a tough alloy steel rather than a high-alloy tool steel: the relatively low carbon content (0.50% vs. D2's 1.50%) means the carbide density is much lower than D2, and the abrasive wear rate on carbide tooling is correspondingly lower. S7 can be productively turned at 300–400 SFM in the annealed condition — significantly faster than D2 — with M-grade carbide and sulfurized semi-synthetic flood coolant. The challenge specific to S7 is work hardening: S7's high chromium content (3.0–3.5%) produces a work-hardening tendency approaching that of austenitic stainless steel. Light, interrupted cuts — such as those that occur when a dull insert begins rubbing rather than cutting — harden the surface rapidly, making each successive pass cut through a progressively harder skin. The prevention strategy: maintain a sharp insert and use positive rake geometry that produces clean shearing rather than rubbing; do not reduce feed below 0.008 ipr on roughing passes (too light a feed produces the rubbing-without-cutting condition); always engage the cut with the full programmed depth of cut rather than gradually increasing depth on successive passes. Hardened S7 (54–56 HRC): CBN turning at 150–250 SFM, light depth of cut (0.005–0.020 inch), continuous air blast. S7's relatively lower carbide content makes it somewhat more amenable to CBN hard turning than D2, though still significantly more demanding than 4340 or H13 at equivalent hardness (Roberts et al., Tool Steels, 5th ed., ASM International, 1998; Machinery's Handbook, 31st ed., Industrial Press, 2020).

The machining sequence for tool steel components that will be hardened to service condition follows the same integrated machining-and-heat-treatment discipline described for alloy steels, but with tighter stock allowances because tool steel distortion during hardening is generally more predictable and more severe than for lower-alloy steels. Recommended sequence for D2 and H13 components: receive material in the annealed condition and verify hardness (255–269 HB for D2, 192–229 HB for H13) before machining — out-of-spec soft material may have been inadequately annealed and will machine inconsistently. Rough machine all features to within 0.050–0.100 inch of finish dimensions. Stress relieve at 1,100–1,150°F for 1 hour per inch of thickness, furnace cool — critical for D2, which retains significant residual stress after rough machining due to its high alloy content. Semi-finish machine to post-hardening stock allowances: 0.010–0.020 inch on bores and critical ODs for D2 after oil quench; 0.015–0.030 inch for H13 (higher because H13 is typically air-hardened from higher temperature and distorts more than oil-quenched D2). Harden per specification. Measure dimensional changes and compare to pre-hardening dimensions. Finish machine using CBN or ceramic tooling at hard turning parameters. The stress relief step between rough machining and hardening is important for complex tool geometries — without it, the residual stress from roughing may produce unexpected distortion during hardening that exceeds the planned stock allowance. UTEC Industrial's car-bottom furnace handles the annealing and stress relieving steps as part of the integrated machining-and-heat-treatment workflow for tool steel components — eliminating the shipping delay and communication gap that accompany outsourced heat treatment (Roberts et al., Tool Steels, 5th ed., ASM International, 1998; ASM Handbook, Vol. 4A, ASM International, 2013).

What safety practices apply specifically to machining tool steel?​

Tool steel machining presents two safety considerations that go beyond standard alloy steel machining: chip handling and grinding dust from dry or near-dry hard turning operations. Tool steel chips (particularly D2 chips, which contain hard carbide fragments): the carbide particles in D2 chips produce chips that are harder and sharper than standard alloy steel chips. The same cut-resistant glove requirements that apply to all chip handling apply here — ANSI/ISEA 105 Level A4 minimum — but D2 chips are specifically more likely to puncture through light-duty cut-resistant materials. Level A6 or higher cut-resistant gloves are recommended for direct D2 chip handling. Grinding and hard turning dust: grinding or hard turning of hardened tool steel (particularly chromium-containing steels like D2 and H13) generates fine metallic and carbide dust containing hexavalent chromium (Cr(VI)) compounds. OSHA 29 CFR 1910.1026 establishes the PEL for Cr(VI) at 5 µg/m³ as an 8-hour TWA, with an action level of 2.5 µg/m³. Engineering controls (local exhaust ventilation at the grinding or turning station, wet operations where applicable) are the primary control; respiratory protection (N95 minimum, P100 for grinding operations) is required when engineering controls cannot reduce exposure below the action level. Grinding dry with D2 or H13 dust accumulating on the machine and floor creates a chronic inhalation hazard — maintaining a wet or vacuum-captured environment for grinding operations is both an OSHA requirement and a practical shop housekeeping standard (OSHA 29 CFR 1910.1026; OSHA 29 CFR 1910.212).

Related Articles

References​

  • Roberts, G., Krauss, G., and Kennedy, R. (1998). Tool Steels, 5th ed. ASM International.
  • ASM International. (1989). ASM Handbook, Volume 16: Machining. ASM International.
  • ASM International. (2013). ASM Handbook, Volume 4A: Steel Heat Treating Fundamentals and Processes. ASM International.
  • Sandvik Coromant. Metalcutting Technical Guide. Sandvik Coromant.
  • Machinery's Handbook, 31st ed. Industrial Press, 2020.
  • OSHA 29 CFR 1910.1026: Chromium (VI) in General Industry. OSHA.

Need Precision CNC Machining?​

UTEC Industrial provides large-scale CNC machining services from our 25,000 sq ft facility in Spokane Valley, WA — equipped with Mazak, Monarch, and Mori Seiki machining centers, plus a gantry bandsaw cutting sections up to 50" × 84".

Request a Quote →

Questions? Call (509) 922-1832 or email sales@utec.co​

Last updated on